Morph a hexahedral mesh of a turbine blade to a new shape

Summary: This example demonstrates how to morph a structural hexahedral mesh of a turbine blade to a new deformed shape defined by a target geometry file.

Objective

This example appends a CDB mesh with a CAD geometry and match morphs the mesh to the geometry.

Procedure

1. Launch an Ansys Prime Server instance and connect the PyPrimeMesh client.

2. Read the mesh and append the new CAD geometry shape.

3. Define the mesh source faces and the target geometry faces to match morph.

4. Match morph the turbine blade mesh to the new CAD geometry shape.

5. Write the mesh for structural analysis.

Launch Ansys Prime Server

Import all necessary modules. Launch the Ansys Prime Server instance and connect the client. Get the client model and instantiate meshing utilities from the lucid class.

import os
import tempfile

import ansys.meshing.prime as prime
from ansys.meshing.prime.graphics import PrimePlotter

prime_client = prime.launch_prime()
model = prime_client.model
mesh_util = prime.lucid.Mesh(model=model)

Using Ansys Prime Server from container ansys-prime-server-7

Read files

Download the turbine blade mesh file and CAD geometry. Read the mesh and append the geometry. Display the source and the target.

# For Windows OS users, scdoc is also available for geometry:
# target_geometry = prime.examples.download_turbine_blade_target_scdoc()

source_mesh = prime.examples.download_turbine_blade_cdb()
target_geometry = prime.examples.download_deformed_blade_fmd()
mesh_util.read(file_name=source_mesh)
mesh_util.read(file_name=target_geometry, append=True)


display = PrimePlotter()
display.plot(model)
display.show()

print(model)

Static Scene

Interactive Scene

Part Summary:

Part Name: blade
Part ID: 2
    0 Edge Zonelets
    6 Face Zonelets
    1 Cell Zonelets

    0 Edge Zones
        Edge Zone Name(s) : []
    0 Face Zones
        Face Zone Name(s) : []
    1 Volume Zones
        Volume Zone Name(s) : [volume]

    5 Label(s)
        Names: [FIRTREE1, FIRTREE2, FIRTREE3, FIRTREE4, PRESSURE_SURF]

    Bounding box (-0.781465 4.39775 -0.7)
                 (0.79353 6.8 0.7)

Part Name: blade_deformed
Part ID: 3
    202 Topo Edges
    80 Topo Faces
    1 Topo Volumes

    0 Edge Zones
        Edge Zone Name(s) : []
    0 Face Zones
        Face Zone Name(s) : []
    1 Volume Zones
        Volume Zone Name(s) : [solid]

    0 Label(s)
        Names: []

    Bounding box (-0.781465 4.39775 -0.7)
                 (0.79353 6.8 0.7)

Define source and target faces

source_part = model.get_part(2)
target_part = model.get_part(3)
source = source_part.get_face_zonelets()
target = target_part.get_topo_faces()

Match morph mesh

Set the target type to be for topoface because the target is geometry. Morph the source face zonelets of source_part to the target topofaces of the geometry.

morpher = prime.Morpher(model)
match_pair = prime.MatchPair(
    model=model,
    source_surfaces=source,
    target_surfaces=target,
    target_type=prime.MatchPairTargetType.TOPOFACE,
)

params = prime.MatchMorphParams(model)
bc_params = prime.MorphBCParams(model)
solver_params = prime.MorphSolveParams(model)

morpher.match_morph(
    part_id=source_part.id,
    match_pairs=[match_pair],
    match_morph_params=params,
    bc_params=bc_params,
    solve_params=solver_params,
)

# Display the morphed mesh

display = PrimePlotter()
display.plot(model, update=True)
display.show()

Static Scene

Interactive Scene

Write mesh

Write the morphed CDB file. The geometry is ignored when exporting to a CDB file.

with tempfile.TemporaryDirectory() as temp_folder:
    mesh_file = os.path.join(temp_folder, "morphed_turbine_blade.cdb")
    mesh_util.write(mesh_file)
    assert os.path.exists(mesh_file)
    print("\nExported file:\n", mesh_file)

This get_abaqus_simulation_data is a beta API. The behavior and implementation may change in future.

Exported file:
 /tmp/tmpb20o80yc/morphed_turbine_blade.cdb

Exit PyPrimeMesh

prime_client.exit()